Szkicownik: Wiązanie prostopadłości
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The Perpendicular Constraint makes two lines to be perpendicular to each other, or two curves to be perpendicular at their intersection. Lines are treated infinite, and arcs are treated as full circles/ellipses. The constraint is also capable of connecting two curves, forcing them perpendicular at the joint, similarly to.
There are four different ways the constraint can be applied:
- between two curves (available not for all curves)
- between two endpoints of a curve
- between a curve and an endpoint of another curve
- between two curves at user-defined point
To apply perpendicular constraint, one should the follow the steps:
- Select two or three entities in the sketch.
- Invoke the constraint by clicking its icon on the toolbar, or selecting the menu item, or using keyboard shortcut.
Between two curves (direct perpendicularity)
Two curves will be made perpendicular at point of their intersection (either real, or of curves' extensions), and the point of intersection will be implicit. This mode is applied if two curves were selected.
- line + line, circle, arc
- circle, arc + circle, arc
If direct perpendicularity between selected curves is not supported (e.g. between a line and an ellipse), a helper point will be added to sketch automatically, and perpendicular-via-point will be applied.
Unlike for tangency, it is perfectly fine to reconstruct the point of perpendicularity by creating a point and constraining it to lie on both curves (thus constraining the point to the intersection).
Between two endpoints (point-to-point perpendicularity)
In this mode, the endpoints are made coincident, and the joint is made to be right angle. This mode is applied when two endpoints of two curves were selected.
- endpoint of line/arc/arc-of-ellipse + endpoint of line/arc/arc-of-ellipse (i.e., two endpoints of any two curves)
Between curve and endpoint (point-to-curve perpendicularity)
In this mode, an endpoint of one curve is constrained to lie on the other curve, and the curves are forced perpendicular at the point. This mode is applied when a curve and an endpoint of another curve were selected.
- line, circle, arc, ellipse, arc-of-ellipse + endpoint of line/arc/arc-of-ellipse (i.e., any curve + endpoint of any curve)
Between two curves at point (perpendicular-via-point) (v0.15)
In this mode, two curves are made perpendicular, and the point of perpendicularity is tracked. This mode is applied when two curves and a point were selected.
- any line/curve + any line/curve + any point
"Any point" can be a lone point, or a point of something, e.g. a center of a circle, an endpoint of an arc, or the origin.
For the constraint to work correctly, the point must be on both curves. So, as the constraint is invoked, the point will be automatically constrained onto both curves (helper constraints will be added, if necessary), and the curves will be forced perpendicular at the point. These helper constraints are plain regular constraints. They can be added manually, or deleted.
Compared to direct perpendicular, this constraint is slower, because there are mode degrees of freedom involved, but it supports ellipses.
The placement of the point before the constraint is applied is a hint for the solver for where the perpendicularity should be.
Ograniczenie prostopadłe może być utworzone przez makropolecenie i z konsoli Pyton za pomocą następujących narzędzi:
# direct perpendicularity Sketch.addConstraint(Sketcher.Constraint('Perpendicular',icurve1,icurve2)) # point-to-point perpendicularity Sketch.addConstraint(Sketcher.Constraint('Perpendicular',icurve1,pointpos1,icurve2,pointpos2)) # point-to-curve perpendicularity Sketch.addConstraint(Sketcher.Constraint('Perpendicular',icurve1,pointpos1,icurve2)) # perpendicular-via-point (plain constraint, helpers are not added automatically) Sketch.addConstraint(Sketcher.Constraint('PerpendicularViaPoint',icurve1,icurve2,geoidpoint,pointpos))
- Sketch jest obiektem szkicu
- icurve1, icurve2 są dwiema liczbami całkowitymi określającymi krzywe, które mają być wykonane prostopadle. Liczby całkowite są indeksami w szkicu (wartość zwracana przez Sketch.addGeometry).
- pointpos1, pointpos2 powinny mieć wartość 1 dla punktu początkowego i 2 dla końcowego.
- geoid point i pointpos w PerpendicularViaPoint są indeksami określającymi punkt prostopadłościanu.