Arkusz blachy: Przykłady

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Wprowadzenie

Środowisko pracy Arkusz Blachy stało się bardzo rozbudowane i wymaga odpowiedniej dokumentacji.

Aby uniknąć przepełnienia stron narzędziowych przykładami, dodano tę stronę w celu zebrania części pokazujących i wyjaśniających specjalne możliwości środowiska Arkusz Blachy.

Zaplanowane etapy tworzenia treści:

  1. Zbieranie zdjęć
  2. Dodawanie opisów przepływów pracy
  3. Dodawanie bardziej szczegółowych samouczków

Zawias

SheetMetal Example-01.png

SheetMetal Example-01a.png SheetMetal Example-01b.png SheetMetal Example-01c.png SheetMetal Example-01d.png

Workflow Hinge: SheetMetal AddBase.svg Make Base Wall, PartDesign Pocket.svg PartDesign Pocket, PartDesign Hole.svg PartDesign Hole, SheetMetal Unfold.svg Unfold.

Hinge step by step

  1. Create a profile (a line and a tangent arc), preferably using the Workbench Sketcher.svg Sketcher Workbench.
  2. Activate the SheetMetal AddBase.svg Make Base Wall command to create a BaseBend object.
  3. Edit the BaseBend object's parameters:
    • Set DANEMid Plane to trueto let the profile extend symmetrically to both sides of the sketch plane.
    • Set DANEradius and DANEthickness to values of your choice.
  4. Create a cut-out contour with the Workbench Sketcher.svg Sketcher Workbench.
  5. Use the PartDesign Pocket.svg PartDesign Pocket command to cut off one half of the Round bit.
  6. Create a hole pattern with the Workbench Sketcher.svg Sketcher Workbench.
  7. Use the PartDesign Hole.svg PartDesign Hole command. Avoid the countersink and counterbore options to keep the body unfoldable.
  8. Activate the SheetMetal Unfold.svg Unfold command to get an Unfold object.
  9. Done!

Klips do papieru

SheetMetal Example-02.png

SheetMetal Example-02a.png SheetMetal Example-02b.png SheetMetal Example-02c.png SheetMetal Example-02d.png

Workflow Paper Clip: SheetMetal AddBase.svg Make Base Wall, SheetMetal SketchOnSheet.svg Sketch on Sheet, clone, flip and fuse, SheetMetal Unfold.svg Unfold.

Paper clip step by step

  1. Create a profile, preferably using the Workbench Sketcher.svg Sketcher Workbench on the XZ plane.
    Profile sketch
  2. Activate the SheetMetal AddBase.svg Make Base Wall command to create a BaseBend object.
  3. Edit the BaseBend object's parameters in the properties panel:
    BaseBend object and highlighted sketch
    • Set DANEMid Plane to trueto let the profile extend symmetrically to both sides of the sketch plane.
    • Set DANElength to 32 mm.
    • Set DANEradius to 2 mm.
    • Set DANEthickness to 0.3 mm.
  4. Select the face between the round sections and activate the Workbench Sketcher.svg Sketcher Workbench.
    Face to support the sketch
  5. To hide the curled part use the Sketcher ViewSection.svg Sketcher View section command.
  6. Create the cut-out contour.
    Cut-out contour Cut-out contour slightly touching the selected face
  7. Finish the sketch using the Sketcher LeaveSketch.svg Sketcher Leave sketch command.
  8. Select the face again and add the Cut-out sketch to the selection.
    Face and sketch selected
  9. Use the SheetMetal SketchOnSheet.svg Sketch on Sheet command to cut around the curled bit.
    Finished first half
  10. One side is finished. We now need to find a way to mirror the body.

Potential mirror options:

  • The PartDesign Mirrored.svg PartDesign Mirrored command fails because it cannot handle SheetMetal features for some reason. So that does not work.
  • The Part Mirror.svg Part Mirror command creates a mirrored part, but this is no longer unfoldable. So that does not work either.
  • One way that can work is to use a clone. This still can't be mirrored, but it can use axial symmetry (turn it 180°).
  • Another way that works is to use a link object.

Mirror using a clone:

  1. Select the body from the tree view.
  2. Use the PartDesign Clone.svg PartDesign Clone command. It adds a new body containing a clone object.
    To apply a 180° turn set the DANEAngle under the Placement property of either the body or the clone to 180°. (Z axis is default and should be fine if you started on the XZ plane as described).
    Cloned half Button right.svg Flipped cloned half
  3. With the body still active, use the PartDesign Boolean.svg PartDesign Boolean operation command to add the body of the clone and fuse both halves.
    Fused halves
  4. Activate the SheetMetal Unfold.svg Unfold command to get an Unfold object.
    Clip and Unfold object Unfold object
  5. Done!

Mirror using a link object:

  1. Select the body from the tree view.
  2. Use the Std LinkMake.svg Make link command. This adds a new link object.
  3. Duplicate the link object by setting the property DANEElement Count to 2.
  4. To apply a 180° turn set the DANEAngle under the Placement property of either of the sub-linked objects to 180°. (Z axis is default and should be fine if you started on the XZ plane as described).
  5. Select both sub-linked objects in the tree view.
  6. Activate the Part Fuse.svg Part Fuse command to fuse both halves.
    Fused halves
  7. Activate the SheetMetal Unfold.svg Unfold command to get an Unfold object.
    Clip and Unfold object Unfold object
  8. Done!

Klamra Omega

SheetMetal Example-03.png

SheetMetal Example-03a.png SheetMetal Example-03b.png SheetMetal Example-03.png SheetMetal Example-03c.png

Workflow Omega Clip: SheetMetal AddBase.svg Make Base Wall, PartDesign Hole.svg PartDesign Hole, PartDesign Fillet.svg PartDesign Fillet, SheetMetal Unfold.svg Unfold.

Sześciokątna miska

SheetMetal Example-04.png

SheetMetal Example-04a.png SheetMetal Example-04b.png SheetMetal Example-04.png SheetMetal Example-04c.png

Workflow Hex Bowl: SheetMetal AddBase.svg Make Base Wall, SheetMetal AddWall.svg Make Wall, 6x SheetMetal AddCornerRelief.svg Add Corner Relief, SheetMetal Unfold.svg Unfold.

SheetMetal Example-04d.png

When a Corner Relief is added (right side) it can be necessary to adjust the value of the Size property.

Klips do długopisu

SheetMetal Example-05.png

SheetMetal Example-05a.png SheetMetal Example-05b.png SheetMetal Example-05c.png SheetMetal Example-05d.png SheetMetal Example-05.png SheetMetal Example-05e.png

Workflow Pen Clip: SheetMetal AddBase.svg Make Base Wall, PartDesign Pocket.svg PartDesign Pocket, 3x SheetMetal AddWall.svg Make Wall, SheetMetal Unfold.svg Unfold.

Przykład przedłużenia ściany

SheetMetal Example-06.png

SheetMetal Example-06a.png SheetMetal Example-06b.png SheetMetal Example-06c.png SheetMetal Example-06.png SheetMetal Example-06d.png

Workflow Extend Face Example: SheetMetal AddBase.svg Make Base Wall, SheetMetal AddWall.svg Make Wall, SheetMetal Extrude.svg Extend Face, SheetMetal Extrude.svg Extend Face, SheetMetal Unfold.svg Unfold.

For the second use of Extend Face a Sketch with two contours is used for shape of the extension(s); and with the value of "use subtraction" set to true it provides the shape for the cut-outs, as well

Korpus złącza USB

SheetMetal Example-07.png

SheetMetal Example-07a.png SheetMetal Example-07b.png SheetMetal Example-07c.png SheetMetal Example-07d.png SheetMetal Example-07.png SheetMetal Example-07e.png

Workflow USB shield contact: SheetMetal AddBase.svg Make Base Wall, SheetMetal Extrude.svg Extend Face, PartDesign Pocket.svg PartDesign Pocket, SheetMetal Extrude.svg Extend Face, SheetMetal AddWall.svg Make Wall, SheetMetal Unfold.svg Unfold.

(The pull relief is just an artistic expression of what could be hidden inside a real plug)

Właściwości środowiska pracy Arkusz Blachy

This section tries to explain the properties of each SheetMetal object with simple images, where applicable.

BaseBend object SheetMetal AddBase.svg

SheetMetal Example-08a.png Button right.svg SheetMetal Example-08b.png

Selected sketch + SheetMetal AddBase.svg Make Base Wall → BaseBend object with default settings


SheetMetal Example-08b.png Button right.svg SheetMetal Example-08c.png

Edit DANElength: Default length → Reduced length


SheetMetal Example-08d.png Button right.svg SheetMetal Example-08h.png

Switch DANEMid Plane from false to true: Extrusion in one direction → Symmetric extrusion


SheetMetal Example-08d.png Button right.svg SheetMetal Example-08e.png

Switch DANEReverse from false to true: Default direction → Inverted direction


SheetMetal Example-08e.png Button right.svg SheetMetal Example-08f.png Button right.svg SheetMetal Example-08g.png

Select DANEBend Side: Outside (default) → Inside Middle


SheetMetal Example-08e.png Button right.svg SheetMetal Example-08i.png

Edit DANEradius: Default radius → Enlarged radius.
This property is the inner radius of the bends created at the vertices where two edges in the sketch have a non-tangential transition.


SheetMetal Example-08e.png Button right.svg SheetMetal Example-08j.png

Edit DANEthickness: Default Thickness → Enlarged thickness