PartDesign Chamfer

From FreeCAD Documentation
Revision as of 20:17, 3 June 2022 by David69 (talk | contribs)
(diff) ← Older revision | Latest revision (diff) | Newer revision → (diff)
Jump to navigation Jump to search
Other languages:
Deutsch • ‎English • ‎Türkçe • ‎español • ‎français • ‎italiano • ‎polski • ‎português do Brasil • ‎română • ‎čeština • ‎русский
Arrow-left.svg Previous: PartDesign Fillet.svg Fillet
Next: Draft PartDesign Draft.svg Arrow-right.svg

PartDesign Chamfer.svg PartDesign Chamfer

Menu location
Part Design → Apply a dress-up feature → Chamfer
Workbenches
PartDesign
Default shortcut
None
Introduced in version
-
See also
PartDesign Fillet

Description

The PartDesign Chamfer.svg PartDesign Chamfer tool creates chamfers on the selected edges of an object. It adds a Chamfer object to the document with its corresponding representation in the Tree view.

Usage

Add a chamfer

  1. Optionally activate the Body to chamfer.
  2. There are several ways to select edges to chamfer:
    • Select one or more edges of the Body individually.
    • Select one or more faces of the Body to select all their edges.
    • Select a feature (usually the last feature) of the Body to select all its edges. introduced in version 0.20
  3. For a chain of tangentially connected edges only a single edge needs to be selected, the chamfer will propagate along the chain.
  4. There are several ways to invoke the tool:
    • Press the PartDesign Chamfer.svg Chamfer button.
    • Select the Part Design → Apply a dress-up feature → PartDesign Chamfer.svg Chamfer option from the menu.
  5. If there is no active Body, and there are two or more Bodies in the document, the Active Body Required dialog will open and prompt you to activate one. If there is a single Body it will be activated automatically.
  6. The Chamfer parameters task panel opens. See Options for more information.
  7. Press the OK button to finish.

Edit a chamfer

  1. Do one of the following:
    • Double-click the Chamfer object in the Tree view
    • Right-click the Chamfer object in the Tree view and select Edit Chamfer from the context menu.
  2. The Chamfer parameters task panel opens. See Options for more information.
  3. Press the OK button to finish.

Options

  • To add edges do one of the following:
    • Press the Add button to start selecting edges and/or faces in the 3D view.
    • To select all remaining edges do the following:
      1. If required press the Add button.
      2. Use the Ctrl+Shift+A keyboard shortcut, or right-click the list and select Add all edges from the context menu. introduced in version 0.20
  • To remove edges do one of the following:
    • Press the Remove button to start deselecting edges and/or faces in the 3D view. Selected elements are highlighted in purple.
    • Select one or more elements in the list and press the Del key, or right-click the list and select Remove from the context menu.
  • Specify a chamfer Type:
    • Equal distance: One distance is used to place both chamfer edges.
    • Two distances: Two distances are used to place the chamfer edges. introduced in version 0.19
    • Distance and angle: A distance is used to place one chamfer edge, the placement of the other chamfer edge is defined by the angle of the chamfer. introduced in version 0.19
  • Press the PartDesign Flip Direction.svg Flip direction button to flip the direction of the chamfer (deactivated for Equal distance). introduced in version 0.19
  • Set the Size of the chamfer.
  • Set the Size2 of the chamfer (only available if Two distances is selected).
  • Set the Angle of the chamfer (only available if Distance and angle is selected).
  • Check the Use all edges checkbox to select all edges of the previous feature. This deactivates the selection list and the related buttons. introduced in version 0.20

Notes

  • PartDesign Chamfer should not be confused with Part Chamfer. Unless you know what you are doing, Part Chamfer should not be used on a PartDesign Body. See Part and PartDesign.
  • Chamfers cannot completely consume the adjacent faces.

Properties

See also: Property editor.

A PartDesign Chamfer object is derived from a Part Feature object and inherits all its properties. It also has the following additional properties:

Data

Base

  • DataBase (LinkSub): Link to the selected edges and faces of the parent feature. Can be a link to only the parent feature if DataUse All Edges is true.
  • DataSupport Transform (Bool): If true the chamfered shape of the additive/subtractive parent feature will be used when the chamfer object is included in a pattern, else only the shape of the chamfer itself will be used. The default is false.
  • Data (hidden)Add Sub Shape (PartShape)
  • Data (hidden)Base Feature (Link): Link to the parent feature.
  • Data (hidden)_ Body (LinkHidden): Link to the parent body.

Chamfer

  • DataChamfer Type (Enumeration): The chamfer type: Equal distance (default), Two distances or Distance and Angle.
  • DataSize (QuantityConstraint): The first chamfer distance. The default is 1 mm.
  • DataSize2 (QuantityConstraint): The second chamfer distance. Only used if DataChamfer Type is Two distances. The default is 1 mm.
  • DataAngle (Angle): The chamfer angle. Only used if DataChamfer Type is Distance and Angle. The default is 45 °.
  • DataFlip Direction (Bool): If true the direction of the chamfer is flipped. Not used if DataChamfer Type is Equal distance. The default is false.
  • DataUse All Edges (Bool): If true all edges of the feature are chamfered, and the edges specified by DataBase are ignored. The default is false.

Part Design

  • DataRefine (Bool): If true redundant edges are removed from the result of the operation. The default value is determined by the Automatically refine model after sketch-based operation preference. See PartDesign Preferences.

Known issues

See PartDesign Fillet.


Arrow-left.svg Previous: PartDesign Fillet.svg Fillet
Next: Draft PartDesign Draft.svg Arrow-right.svg