SheetMetal AddWall

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AddBase

Next: Extrude

SheetMetal Workbench

Menu location
SheetMetal AddWall
SheetMetal → Make Wall
Workbenches
SheetMetal
Default shortcut
W
Introduced in version
-
See also
None
Contents 1 Description 2 Usage 3 Notes 4 Properties 4.1 Data 5 Example 5.1 Preparation 5.2 Workflow

Description

The SheetMetal AddWall command creates flanges on selected edges of a base plate. By changing the Dataangle property a flange it can be turned into a hem.

A flange consists of a 90° cylindrical bend and a planar strip (wall).

Two selected edges → two flanges

Resetting the Dataangle property to about 180° in a second step will create a hem instead.

Two selected edges → two hems

Usage

Select one or more edge(s) of a base plate.
Activate the SheetMetal AddWall command using one of the following:
- The Make Wall button.
- The SheetMetal → Make Wall menu option.
- The keyboard shortcut: W.

Notes

To create a base plate use a closed 2D outline - preferably a Sketch - with the Make Base Wall command.

Alternatively a base plate (blank) can be created with commands from the Part Workbench or PartDesign Workbench.

To create a blank with the Part Workbench:

Create a solid using either:
- Part Box.
- Part Extrude from:
  - A Draft Rectangle.
  - A Draft Wire.
  - A Sketch.
Make sure one the dimensions of the Box or the extrusion distance equals the sheet metal thickness.

To create a blank with the PartDesign Workbench:

Create a solid using either:
- Additive Box.
- PartDesign Pad from a Sketch.
Make sure one the dimensions of the Box or the DataLength property of the Pad equals the sheet metal thickness.

If you start with a PartDesign Body, you can mix SheetMetal features with PartDesign features such as PartDesign Pocket or PartDesign Hole.

Properties

Data

Base

DataLabel (String): Default value: Bend (+ a sequential number for second and following items).
The user editable name of this object, it may be any arbitrary UTF8 string.
Data (hidden)Base Feature (Link): Base Feature. Link to the parent feature.
Data (hidden)_Body (LinkHidden): Hidden link to the parent body.

Parameters

DataBend Type (Enumeration): "Bend Type". Material Outside (default), Material Inside, Thickness Outside, Offset.
Dataangle (Angle): "Bend Angle". Default angle: 90,00°.
Database Object (LinkSub): "Base Object". Link to the planar face to receive a bend.
Datagap1 (Distance): "Gap from Left side". Default: 0,00 mm.
Datagap2 (Distance): "Gap from Right side". Default: 0,00 mm.
Datainvert (Bool): "Invert Bend Direction". Default: false.
Datalength (Length): "Length of Wall". Default: 10,00 mm.
Dataradius (Length): "Bend Radius". Default: 1,00 mm.

Parameters Ex

DataAuto Miter (Bool): "Enable Auto Miter". Default: true.
Dataextend1 (Distance): "Extend from Left Side". Default: 0,00 mm.
Dataextend2 (Distance): "Extend from Right Side". Default: 0,00 mm.
Datakfactor (FloatConstraint): "Location of Neutral Line. Caution: Using ANSI standards, not DIN.".
Default: 0,50. K factor (also known as neutral factor) for the bend. Used to calculate bend allowance when unfolding.
Datamax Extend Dist (Length): "Auto Miter maximum Extend Distance". Default: 5,00 mm.
Datamin Gap (Length): "Auto Miter Minimum Gap". Default: 5,00 mm.
Datamiterangle1 (Angle): "Bend Miter Angle from Left Side". Default angle: 0,00°.
Datamiterangle2 (Angle): "Bend Miter Angle from Right Side". Default angle: 0,00°.
Dataoffset (Distance): "Offset Bend". Default: 0,00 mm.
Dataunfold (Bool): "Shows Unfold View of Current Bend". Default: false
true unfolds the bend.

Parameters Ex2

DataSketch (Link): "Sketch Object".
Datasketchflip (Bool): "Flip Sketch Direction". Default: false.
Datasketchinvert (Bool): "Invert Sketch Start". Default: false.

Parameters Ex3

DataLength List (FloatList): "Length of Wall List". Default: [10,00].
Databend AList (FloatList): "Bend Angle List". Default: [90,00].

Parameters Relief

DataRelief Factor (Float): "Relief Factor". Default: 0,70.
DataUse Relief Factor (Bool): "Use Relief Factor". Default: false.
Datamin Relief Gap (Length): "Minimum Gap to Relief Cut". Default: 1,00 mm.
Datarelief Type (Enumeration): "Relief Type". Rectangle (default), Round. Enabled only when a gap value is set.
Datareliefd (Length): "Relief Depth". Default: 1,00 mm. Enabled only when a gap value is set.
Datareliefw (Length): "Relief Width". Default: 0,80 mm. Enabled only when a gap value is set.

Example

A simple tray

Preparation

This tray is made of a rectangular blank with walls added to its outline edges. And so one outline sketch for the blank has to be prepared in advance.

Just a rectangular outline

Workflow

Create a blank
1. Select the outline sketch
2. Press the Make Base Wall button
  or use the keyboard shortcut: C then F
  
  (The blank is padded in z direction
Add walls to the outline edges
1. Select the blank's outline edges
2. Press the Make Wall button
  or use the keyboard shortcut: W
3. If the fold is 90° down set the value of invert property to true to reverse the direction (and length to a lower value for smaller walls)
Add some more walls
1. Select the tray's upper outside edges
2. Press the Make Wall button
  or use the keyboard shortcut: W
3. The walls are a bit too long (but nicely trimmed) and so the length property has to be set to a lower value
4. If you like the folds swing outward set the invert value to true